The Fan condition is used to define the flow direction (inlet or outlet) and the fan parameters on exterior boundaries. The
Interior Fan condition is available on interior boundaries.
The Flow direction can be set to
Inlet or
Outlet. When a boundary has been selected, an arrow displays in the
Graphics window to indicate the selected flow direction. The arrow can be updated if the selection changes by clicking any node in the
Model Builder and then clicking the
Fan node again to update the
Graphics window.
The Inlet Flow direction controls in which direction the fluid enters the domain.
When Inlet is selected as the
Flow direction, the
Input pressure pinput defines the pressure at the fan inlet.
When Outlet is selected as the
Flow direction, the
Exit pressure pexit defines the pressure at the fan outlet.
When Include gravity is selected and
Use reduced pressure is not selected in the interface’s
Physical model section, the
Compensate for hydrostatic pressure (named
Compensate for hydrostatic pressure approximation for weakly compressible or compressible flow) check box is available and selected by default. When it is selected, the hydrostatic pressure is automatically added to the pressure entered in
pinput or
pexit user input.
For both Inlet and
Outlet flow directions, if
Linear is selected, values or expressions for the
Static pressure at no flow pnf and the
Free delivery flow rate V0,fd should be specified. The static pressure curve is equal to the static pressure at no flow rate when
V0 < 0 and equal to 0 when the flow rate is larger than the free delivery flow rate.
With the User defined option, a different value or expression for the
Static pressure curve can be specified. The flow rate across the selection where this boundary condition is applied is defined by
phys_id.V0 where
phys_id is the name (for example,
phys_id is
spf by default for laminar single-phase flow). In order to avoid unexpected behavior, the function used for the fan curve returns the maximum of the user-defined function and 0.
The Static pressure curve data can be entered or loaded under the
Static Pressure Curve Data section that displays for this option. The interpolation between points given in the table is defined using the
Interpolation function type list in the
Static Pressure Curve Interpolation section.
This section is available when Static pressure curve data is selected as the
Static pressure curve. Units can be specified for the
Flow rate and
Static pressure.
When Static pressure curve data is selected as the
Static pressure curve, a table appears, where values or expressions the
Flow rate and
Static pressure can be specified or imported from a text file by clicking the
Load from file button (
) under the table. Units can be specified for the
Flow rate and the
Static pressure curve.
This section is available when Static pressure curve data is selected as the
Static pressure curve. The available options for the
Interpolation function type are
Linear,
Piecewise cubic, and
Cubic spline.
When Inlet is selected as the
Flow direction and the
Turbulence model has transport equations for the turbulent kinetic energy,
k, and turbulent dissipation rate,
ε, specific dissipation rate,
ω, or turbulent relative fluctuations,
ζ, the values of the
Turbulent kinetic energy,
Turbulent relative fluctuations (for the v2-f turbulence model) and the
Turbulent dissipation rate or
Specific dissipation rate on the downstream side of the fan should be specified. Alternatively, the
Reference velocity scale can be used to specify default values.